DriveWorks Solo 15: Cut Features [send feedback...]

Introduction

This document describes the types of rules that can be applied to models that have advanced feature parameters captured.

Driving advanced feature dimensions increases model generation time. Where possible capture feature dimensions (distances, numbers and angles) as dimensions rather than an advanced feature parameter.

During model generation captured dimensions are driven before captured advanced feature parameters. If the advanced feature parameter has also been captured as a dimension the value being driven into the advanced feature parameter will override the captured dimension.

Cut Extrude

ParameterTypeDescription
D1DepthDistanceSet the Depth for the extrusion in direction 1. In the case of an OffsetFromSurface end condition, set the offset distance in direction 1.
D1DraftAngleAngleSet the draft angle of a drafted extrusion in direction 1
D1ApplyDraftTrue/FalseSet whether a draft is applied to the extrusion in direction 1
D1DraftOutwardsTrue/FalseSet a drafted extrusion in direction 1 to draft outwards
D1EndCondition

One of the following values:

Blind

ThroughAll

UpToNext

MidPlane

Define the extrusion with D1Depth

Set the feature to extrude through all features above the sketch plane in direction 1

Set the feature to extrude up to the next surface above the sketch plane in direction 1

Set the feature to extrude in both directions from the sketch plane with a total extrusion depth defined by D1Depth

D1ReverseOffsetTrue/FalseFor an OffsetFromSurface end condition extrusion, set the direction in which the offset is applied
D1TranslateSurfaceTrue/FalseFor an OffsetFromSurface end condition extrusion, set the end of the extrusion to be a translation of the reference surface
BothDirectionsTrue/FalseEnable the feature to extrude in both direction 1 and direction 2
D2DepthDistanceSet the Depth for the extrusion in direction 2. In the case of an OffsetFromSurface end condition, set the offset distance in direction 2.
D2DraftAngleAngleSet the draft angle of a drafted extrusion in direction 2
D2ApplyDraftTrue/FalseSet whether a draft is applied to the extrusion in direction 2
D2DraftOutwardsTrue/FalseSet a drafted extrusion in direction 2 to draft outwards
D2EndCondition

One of the following values:

Blind

ThroughAll

UpToNext

Define the extrusion with D2Depth

Set the feature to extrude through all features above the sketch plane in direction 2

Set the feature to extrude up to the next surface above the sketch plane in direction 2

D2ReverseOffsetTrue/FalseFor an OffsetFromSurface end condition extrusion, set the direction in which the offset is applied
D2TranslateSurfaceTrue/FalseFor an OffsetFromSurface end condition extrusion, set the end of the extrusion to be a translation of the reference surface
FromType

One of the following values:

SketchPlane

Offset

Set the starting end of the extrusion to be coincident with the sketch plane

Set the starting end of the extrusion to be offset from the sketch plane

FromOffsetDistanceDistanceSet the offset distance for an offset start condition extrusion
FromOffsetReverseTrue/FalseSet the direction in which the offset is applied for an offset start condition extrusion
FlipSideToCutTrue/FalseRemoves all material from the outside of the profile. By default, material is removed from the inside of the profile.
ReverseDirectionTrue/FalseSet the direction in which a single direction extrusion extends from the sketch plane

Cut Extrude Thin

ParameterTypeDescription
D1DepthDistanceSet the Depth for the extrusion in direction 1. In the case of an OffsetFromSurface end condition, set the offset distance in direction 1.
D1DraftAngleAngleSet the draft angle of a drafted extrusion in direction 1
D1ApplyDraftTrue/FalseSet whether a draft is applied to the extrusion in direction 1
D1DraftOutwardsTrue/FalseSet a drafted extrusion in direction 1 to draft outwards
D1EndCondition

One of the following values:

Blind

ThroughAll

UpToNext

MidPlane

Define the extrusion with D1Depth

Set the feature to extrude through all features above the sketch plane in direction 1

Set the feature to extrude up to the next surface above the sketch plane in direction 1

Set the feature to extrude in both directions from the sketch plane with a total extrusion depth defined by D1Depth

D1ReverseOffsetTrue/FalseFor an OffsetFromSurface end condition extrusion, set the direction in which the offset is applied
D1TranslateSurfaceTrue/FalseFor an OffsetFromSurface end condition extrusion, set the end of the extrusion to be a translation of the reference surface
BothDirectionsTrue/FalseEnable the feature to extrude in both direction 1 and direction 2
D2DepthDistanceSet the Depth for the extrusion in direction 2. In the case of an OffsetFromSurface end condition, set the offset distance in direction 2.
D2DraftAngleAngleSet the draft angle of a drafted extrusion in direction 2
D2ApplyDraftTrue/FalseSet whether a draft is applied to the extrusion in direction 2
D2DraftOutwardsTrue/FalseSet a drafted extrusion in direction 2 to draft outwards
D2EndCondition

One of the following values:

Blind

ThroughAll

UpToNext

Define the extrusion with D2Depth

Set the feature to extrude through all features above the sketch plane in direction 2

Set the feature to extrude up to the next surface above the sketch plane in direction 2

D2ReverseOffsetTrue/FalseFor an OffsetFromSurface end condition extrusion, set the direction in which the offset is applied
D2TranslateSurfaceTrue/FalseFor an OffsetFromSurface end condition extrusion, set the end of the extrusion to be a translation of the reference surface
FromType

One of the following values:

SketchPlane

Offset

Set the starting end of the extrusion to be coincident with the sketch plane

Set the starting end of the extrusion to be offset from the sketch plane

FromOffsetDistanceDistanceSet the offset distance for an offset start condition extrusion
FromOffsetReverseTrue/FalseSet the direction in which the offset is applied for an offset start condition extrusion
ReverseDirectionTrue/FalseSet the direction in which a single direction extrusion extends from the sketch plane
Thin Wall Type

One of the following values:

OneDirection

OppDirection

MidPlane

TwoDirection

Set the wall to be of Primary Wall Thickness from the sketch line

Set the wall to be of Primary Wall Thickness from the sketch line in the opposite direction

Set the wall to be of Primary Wall Thickness with the sketch line at the mid point of the thickness

Set the wall to be of Primary Wall Thickness from the sketch line in direction 1 and of Secondary Wall Thickness in direction 2

Primary Wall ThicknessDistanceSet the thickness of the thin feature in the primary direction
Secondary Wall ThicnkessDistanceSet the secondary wall thickness in a TwoDirection Thin Wall Type thin feature

Revolved Cut

ParameterTypeDescription
D1AngleAngleSet the revolution angle in direction 1
D2AngleAngleSet the revolution angle in direction 2
ReverseDirectionTrue/FalseSet the direction around the axis in which direction 1 extends
Type

One of the following values:

OneDirection

Midplane

TwoDirection

360Degrees

Creates a single direction revolve

Creates a revolve in both directions, extending half of D1Angle in each direction

Creates a revolve in both directions, defined by D1Angle and D2Angle

Creates a 360 degree revolve

Revolved Cut Thin

ParameterTypeDescription
D1AngleAngleSet the revolution angle in direction 1
D2AngleAngleSet the revolution angle in direction 2
ReverseDirectionTrue/FalseSet the direction around the axis in which direction 1 extends
Primary Wall ThicknessDistanceSet the thickness of the thin feature in the primary direction
Secondary Wall ThicknessDistanceSet the secondary wall thickness in a TwoDirection Thin Wall Type thin feature
Type

One of the following values:

OneDirection

Midplane

TwoDirection

360Degrees

Creates a single direction revolve

Creates a revolve in both directions, extending half of D1Angle in each direction

Creates a revolve in both directions, defined by D1Angle and D2Angle

Creates a 360 degree revolve

ThinWallType

One of the following values:

OneDirection

OppDirection

Midplane

TwoDirection

Set the wall to be of Primary Wall Thickness from the sketch line

Set the wall to be of Primary Wall Thickness from the sketch line in the opposite direction

Set the wall to be of Primary Wall Thickness with the sketch line at the mid point of the thickness

Set the wall to be of Primary Wall Thickness from the sketch line in direction 1 and of Secondary Wall Thickness in direction 2

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